Hi guys
I need a little help with this code.
I can set axes A to 0.000 and it starts
running the part from that postion.
The next postion is A-135 and it will
go to that postion and everything is
on track after that but it completely
skips A-90.
There is a fixture in the tailstock that
has to be indexed.
Now I can set the fixture to the A-90
postion and start the job and all is well
but this is a pain.
The fixture has a indexing mark to set it at
A-0.000 for seting up the part.
Why dosen't the A axes move to A-90
from A-0.0 then start running the job?


G00 G43 G40.1 G17 G80 G50 G90
G20
(Rotate Table)
A-90. F1.
(Standard Drill 90)
M6 T1
G43 H1
M03 S4500
G00 Z0.2500
X3.0469 Y-0.0001
G81 X3.0469 Y-0.0001 Z-0.2512 R0.0988
G80
G00 Z0.2500
G81 X5.0156 Y-0.0002 Z-0.2698 R0.0802
G80
G00 Z0.2500
G81 X6.9844 Y-0.0001 Z-0.261 R0.089
G80
G00 Z0.2500
G81 X8.9531 Y-0.0001 Z-0.261 R0.089
G80
G00 Z0.2500
(Rotate Table)
A-135. F1.
(Standard Drill 135)
X2.0625
G81 X2.0625 Y-0.0001 Z-0.2643 R0.0857
G80
G00 Z0.2500
G81 X4.0312 Y-0.0001 Z-0.2643 R0.0857
G80
G00 Z0.2500
G81 X6.0000 Y-0.0001 Z-0.2643 R0.0857
G80
G00 Z0.2500
G81 X7.9687 Y-0.0001 Z-0.2643 R0.0857
G80
G00 Z0.2500
G81 X9.9375 Y-0.0001 Z-0.2643 R0.0857
G80
G00 Z0.2500
(Clearance Plane)
A-180. F1.
(Standard Drill 180)
X3.0469 Y0.0000
G81 X3.0469 Y0.0000 Z-0.2513 R0.0987
G80
G00 Z0.2500
G81 X5.0156 Y0.0000 Z-0.2513 R0.0987
G80
G00 Z0.2500
G81 X6.9844 Y0.0000 Z-0.2501 R0.0999
G80
G00 Z0.2500
G81 X8.9531 Y0.0000 Z-0.2611 R0.0889
G80
G00 Z0.2500
(Rotate Table)
A-225. F1.
(Standard Drill 225)
X2.0625 Y0.0001
G81 X2.0625 Y0.0001 Z-0.2643 R0.0857
G80
G00 Z0.2500
G81 X4.0312 Y0.0001 Z-0.2643 R0.0857
G80
G00 Z0.2500
G81 X6.0000 Y0.0001 Z-0.2643 R0.0857
G80
G00 Z0.2500
G81 X7.9687 Y0.0001 Z-0.2643 R0.0857
G80
G00 Z0.2500
G81 X9.9375 Y0.0001 Z-0.2643 R0.0857
G80
G00 Z0.2500
(Rotate Table)
A-270. F1.
(Standard Drill 270)
X3.0469
G81 X3.0469 Y0.0001 Z-0.25 R0.1
G80
G00 Z0.2500
G81 X5.0156 Y0.0002 Z-0.2698 R0.0802
G80
G00 Z0.2500
G81 X6.9844 Y0.0001 Z-0.261 R0.089
G80
G00 Z0.2500
G81 X8.9531 Y0.0001 Z-0.261 R0.089
G80
G00 Z0.2500
(Rotate Table)
A-0. F1.
(2 1/2 Axis Profiling)
M5 M6 T2
G43 H2
M03 S4500
X12.1000 Y0.4394
G01 Z-0.3750  F20.0
X12.0500  F25.0
X12.0000  F30.0
X2.0138  F10.0
Y-0.4394
X12.0000
X12.0500  F30.0
X12.1000
G00 Z0.0750
Y0.4894
G01 Z-0.3750  F20.0
X12.0500  F25.0
X12.0000  F30.0
X1.9638  F10.0
Y-0.4894
X12.0000
X12.0500  F30.0
X12.1000
G00 Z1
M5 M9
M30

THere is NO G0 or G1 to tell it to move. THe move command only become modal after it is called once.

(;-) TP

Thanks !
Could you edit the code for an example if you don't mind.

It looks like I'll have to edit my post processer file to correct this.

G00 G43 G40.1 G17 G80 G50 G90
G20
(Rotate Table)
G0   A-90. F1.      ( add a G0 at this point)         
(Standard Drill 90)
M6 T1
G43 H1
M03 S4500
G00 Z0.2500
X3.0469 Y-0.0001
G81 X3.0469 Y-0.0001 Z-0.2512 R0.0988
G80
G00 Z0.2500
G81 X5.0156 Y-0.0002 Z-0.2698 R0.0802
G80
G00 Z0.2500
G81 X6.9844 Y-0.0001 Z-0.261 R0.089
G80
G00 Z0.2500
G81 X8.9531 Y-0.0001 Z-0.261 R0.089
G80
G00 Z0.2500
(Rotate Table)
A-135. F1.

Thank you so much!!!

Run the job today with that code change
and all is well !!!